Tap Drill Size Chart (M2 to M24)

The Main Cause of Tap Breakage
The most frequent cause of tap breakage is not operator skill but an error in selecting the tap drill (pilot hole) diameter.
- When the diameter is too small — The volume the tap must cut increases. An undersize of 0.1~0.2 mm raises torque nonlinearly by 15~25%, and when tool wear is added the tap reaches its breaking threshold. The risk is greatest in hard materials such as stainless steel.
- When the diameter is too large — The tap will not break, but thread engagement becomes shallow. Holding strength drops and the threads shear under load.
In other words, the pilot hole is not a dimension to which you add margin; it is a dimension that must match the specified value. The common belief that "it is safer to drill the hole larger" does not apply.
Thread Engagement
As the pilot hole diameter increases, the depth of thread engagement decreases. This is called thread engagement.
The key point is that 100% engagement is not the optimum. Quantitatively:
- At 70~75% engagement you already get about 93~98% of the strength of 100%
- Increasing to 100% yields only a 5~7% strength gain
- Meanwhile, tapping torque rises by more than 3 times
Standard pilot hole dimensions are designed to target this 70~75% point. Reducing the pilot hole "to fasten more securely" is therefore a choice that gains little strength and only increases the risk of breakage.
Adjusting Engagement by Material
| Base material | Recommended engagement | Reason |
|---|---|---|
| Soft materials such as aluminum | 75~83% | Base material strength is low, so engagement is increased |
| General steel | 70~75% | Standard |
| Hardened steel, stainless steel | 50~65% | Reducing torque takes priority |
Pilot Hole Diameters for Metric Coarse Threads
The working rule for calculation is as follows.
Drill diameter ≈ nominal diameter − pitch
This is an approximation that targets 70~75% engagement.
| Designation | Pitch (mm) | Pilot drill (mm) |
|---|---|---|
| M2 | 0.4 | 1.6 |
| M2.5 | 0.45 | 2.05 |
| M3 | 0.5 | 2.5 |
| M4 | 0.7 | 3.3 |
| M5 | 0.8 | 4.2 |
| M6 | 1.0 | 5.0 |
| M8 | 1.25 | 6.8 * |
| M10 | 1.5 | 8.5 |
| M12 | 1.75 | 10.3 * |
| M14 | 2.0 | 12.0 |
| M16 | 2.0 | 14.0 |
| M18 | 2.5 | 15.5 |
| M20 | 2.5 | 17.5 |
| M22 | 2.5 | 19.5 |
| M24 | 3.0 | 21.0 |
* The M8 and M12 values are the approximation results (6.75 / 10.25) rounded to standard drill sizes. For M12, some references use 10.2. The other 13 designations match the calculated values.
This table does not apply to fine threads (M8×1.0, etc.). The pitch differs, so recalculate with the same rule.
Thread Depth
It is common for a drawing to say only "M6 tap" and omit the depth. The depth criterion depends on the strength of the base material.
| Base material | Recommended depth | Basis |
|---|---|---|
| Steel (steel-to-steel fastening) | 1.0 × nominal diameter | Base material strength is sufficient |
| Stainless steel | approx. 1~1.5 × nominal diameter | — |
| Aluminum (6061-T6, etc.) | 1.5~2.0 × nominal diameter | Base material strength is low, so engagement length is increased |
| Plastic | 2~2.5 × nominal diameter | Consider using an insert |
Making It Deeper Does Not Increase Holding Strength
Axial load is not distributed evenly across all threads. Studies show that the first thread carries about 34% of the axial load and the second about 23%, and the first 3~4 threads carry about 70~80% of the total load.
Therefore, machining beyond the specified depth does not meaningfully increase holding strength and only adds machining time and the risk of tap breakage.
Blind Holes
In a through hole, chips are ejected downward, but a blind hole has no escape path for chips. Chips that pack at the bottom bind the tap and lead to breakage.
Also, the chamfered lead of the tap has incomplete threads. So the depth at which full threads form is shallower than the drilled depth.
Drill Depth Depends on Tap Type
Drill depth = effective thread depth + tap chamfer length + chip space (2~3 × pitch)
| Tap type | Chamfer length | Suitability for blind holes |
|---|---|---|
| Bottoming | 1.5~2 pitches | Suitable — forms threads close to the bottom |
| Plug | 3~5 pitches | Extra depth required |
| Taper | 7~10 pitches | For through holes |
So the "2~3 pitches of clearance" applies to a bottoming tap; with a plug or taper tap you must drill correspondingly deeper. On the drawing, give the two values separately.
- Effective thread depth — The depth at which full threads are required
- Drill depth — Effective depth + chamfer + chip space
Example note: M6 effective depth 10, drill φ5 depth 14
If the geometry allows a through hole, prefer it. It is better for both cost and process stability.
Frequently Asked Questions
Is it acceptable to drill 0.1 mm larger?
Generally yes. Engagement drops slightly, but the strength loss is small and the tap load decreases greatly. Conversely, a 0.1 mm reduction raises torque nonlinearly and increases the risk of breakage.
What happens if the tap breaks inside the hole?
Taps are made of high-hardness material, so they cannot be removed with an ordinary drill. The drill slips and pushes the fragments further in. The options are as follows.
- Remove by dissolving with electrical discharge machining (EDM)
- Remove with a dedicated carbide tool
- Apply a chemical dissolving agent
- Enlarge the hole and repair with a Helicoil or insert
- If none of the above is possible, scrap the part
Either way there is a cost, so getting the pilot hole accuracy right turns out to be the lowest-cost option.
What if aluminum needs repeated fastening?
Aluminum threads are vulnerable to repeated fastening. Consider using a Helicoil or insert and specify it on the drawing.
Summary
- Match the pilot hole to the specified value. Reducing it makes torque climb sharply
- 70~75% engagement is enough. 100% gives a 5~7% strength gain for 3 times the torque
- Depth is 1.0D for steel / 1.5~2.0D for aluminum. The first 3~4 threads carry 70~80% of the load, so machining beyond that is pointless
- For blind holes, give the drill depth and effective thread depth separately and consider the tap type
Upload a drawing to check the pilot hole and tapping feasibility for the specified thread.
Have a part to machine?
Upload a drawing to see your quote.



