본문 바로가기
Guides

Metric Thread Size Chart (M2 to M24)

Spec chartsCNC machiningSep 10, 2026

If a drawing says only "M6", the manufacturer assumes a coarse thread, through hole, with depth equal to the plate thickness. Whenever the fine/coarse pitch, the depth, or whether it is an inch thread is missing, a confirmation call follows. This page gathers the numbers you need when specifying a thread in one table. Tap drill diameters are in a separate Tap Drill Size Chart.

Metric Coarse Thread Chart

Units in mm. Minor diameter is an approximate value for the internal thread.

ThreadPitchMinor diameterEffective depth
(steel 1D)
M20.401.572
M2.50.452.012.5
M30.502.463
M40.703.244
M50.804.135
M61.004.926
M81.256.658
M101.508.3810
M121.7510.1112
M162.0013.8416
M202.5017.2920
M243.0020.7524

Fine Threads: Always State the Pitch on the Drawing

ThreadCoarse pitchFine pitch
M81.251.0
M101.51.25 / 1.0
M121.751.5 / 1.25
M162.01.5
M202.51.5
M243.02.0

Write a fine thread with the pitch attached, as in "M10×1.25". Without the pitch, it is machined as a coarse thread. Use fine threads when cutting threads in thin walls, when the fastener must not loosen from vibration, and for fine-adjustment screws.

Effective Thread Depth: Recommended Values by Material

Female thread materialRecommended depthM6 example
Steel (SS400 (mild steel, similar to ASTM A36), S45C (1045 carbon steel))1.0D6 mm
Cast iron1.25D7.5 mm
Aluminum1.5 to 2.0D9 to 12 mm
Plastic2.0D or more12 mm or more

D is the nominal thread diameter. Increasing the depth does not increase clamping force proportionally. The load is carried by the first few threads. For repeated fastening in aluminum, reinforcement is more practical than depth (Helicoil vs. Insert Nut).

Inch Threads and Metric Equivalents

Inch (UNC)Threads per inchClosest metric
#4-4040M3
#6-3232M3.5
#8-3232M4
#10-2424M5
1/4-2020M6
5/16-1818M8
3/8-1616M10
1/2-1313M12

The equivalent means a similar size, not that they are interchangeable. For locations that must match US-made equipment or parts, write the inch thread as is, "1/4-20 UNC". If you convert it to metric, the bolt will not fit.

Order for Specifying a Thread on a Drawing

  • Designation and pitch: M10×1.25
  • Depth: "thru" for a through hole; for a blind hole, give "depth 15" (thread depth) and the drill depth separately
  • Quantity and position: put the count first, as in "4-M6 thru"
  • If a class is needed, 6H (internal thread) and 6g (external thread); for general parts it can be omitted and is still machined to 6H/6g

Frequently Asked Questions

How much extra drill depth does a blind-hole thread need?

Add 2 to 3 times the pitch to the thread depth. For M6 (pitch 1.0) with a thread depth of 10, the drill depth is 12 to 13. This is because of the incomplete thread at the end of the tap.

Can threads M3 and smaller be CNC machined?

Yes. However, at M2 and below the risk of tap breakage is high and the cost per piece rises. Design with M2.5 or larger where possible.

Can inch threads be machined?

Yes. Just write UNC or UNF and the thread count on the drawing. Lead time may be longer depending on whether the inch tap is in stock.

Summary

A thread is fully defined only with four items: designation, pitch, depth, and quantity. Attach the pitch for fine threads, write inch threads in inches, and for aluminum look at reinforcement instead of depth.

See Also

You can continue from the hole for the thread through to reinforcement.

Source standards: KS B ISO 261 and 262 (metric thread designation and pitch), KS B ISO 724 (basic dimensions). Minor diameter is based on the internal thread bore D1. Effective depth is a design practice value.

Have a part to machine?

Upload a drawing to see your quote.

Sponsorship & lab support

From competition prep to research projects,
we build alongside student teams and labs.

Questions?

KakaoTalk chat
031-509-0523