Laser Cutting vs. Press Blanking

The Short Answer
- No die → laser cutting. With only a drawing, you can cut today.
- Enough quantity to spread the die cost → press blanking. The unit price becomes incomparably lower.
- The deciding factor is not the first order quantity but how many of this part you will make in total.
The two methods accumulate cost along different axes. So neither is always cheaper, and the two cost lines must cross once along the quantity axis.
The Cost Structures Differ
Laser cutting needs no die. Instead, the beam must travel around the contour once for every part. The per-part cost is proportional to the following factors.
- Contour length (total length of the cut line)
- Sheet thickness (the thicker, the slower the speed)
- Number of pierces (the time to first punch through for each hole)
- Assist gas
The key point is that the per-part cost barely falls as quantity increases. The 100th part must go around the contour just like the first.
Press blanking is the opposite. You must build a die before you can start, and this die cost is a fixed cost independent of quantity. But once the die is up, each press stroke produces one part. Whether the contour is complex or has many holes, it is one stroke. The per-part processing cost is an order of magnitude different from laser.
Laser cost per part = cutting cost per part (roughly constant regardless of quantity)
Blanking cost per part = (die cost ÷ total quantity) + press cost per part
Calculating the Break-Even Quantity
Setting the two equations equal gives the crossover point.
Break-even quantity = die cost ÷ (laser cost per part − blanking press cost per part)
The denominator is the amount saved per part by switching to blanking. Dividing the die cost by this saving tells you how many parts you must make to recover the die cost.
This example shows the structure. The numbers below are assumed values to explain the calculation, not actual quotes.
Assume a die cost of 3 million KRW, laser at 2,000 KRW per part, and blanking at 200 KRW per part. The saving per part is 1,800 KRW, and the break-even is 3,000,000 ÷ 1,800 ≈ 1,667 parts. Below 1,667 parts, laser is cheaper in total; above it, blanking is.
What matters here is not the numbers but the sensitivity.
- The smaller and simpler the part, the lower the laser cost per part, the smaller the denominator, and the higher the break-even quantity. In other words, the die does not pay off without a substantial quantity.
- The larger the part, the longer the contour, and the more holes it has, the higher the laser cost per part, the larger the denominator, and the faster the break-even quantity falls. For a sheet with dozens of holes, piercing time accumulates in laser cutting, so switching to blanking becomes advantageous much sooner.
The more holes a part has, the earlier the blanking crossover comes. This is the judgment used most often in practice.
Comparison
| Item | Laser cutting | Press blanking |
|---|---|---|
| Upfront cost | None (drawing only) | Die cost |
| Processing time per part | Proportional to contour length, thickness, and number of pierces | Constant at 1 stroke |
| Effect of shape complexity | Large (longer lines cost more) | Almost none |
| Design changes | Immediate, just edit the drawing | Die modification or remake |
| Lead time | Short | Die build time comes first |
| Cut edge | Heat-affected zone (HAZ) present | Rollover, shear zone, fracture zone, burr |
| Thickness limit | Depends on machine power | Depends on die and press tonnage |
| Favorable quantity | Small to medium quantities | Large, repeat orders |
Four Factors Beyond Quantity That Can Flip the Decision
Deciding on break-even calculation alone can be wrong.
1. Calculate with total lifetime quantity. Even if the first order is 500 parts, a part used at 500 per year for 3 years totals 1,500. Once built, the die can be reused on reorders, so from the second order the die cost enters as zero. Judging only by the first order quantity means cutting by laser every time and ending up paying more.
2. A die is risky if the design is not finalized. A die is hard to change once built. Even moving one hole costs a modification, and a major shape change means building a new one. For a part still being validated, going with laser is safer in total cost even at high quantity.
3. Cut edge quality requirements differ. Laser cuts by melting with heat, so a heat-affected zone remains. For mild steel it is roughly 0.13–0.25mm. It is often not a problem when the part is later welded or painted, but it needs review when the cut edge itself is a functional surface or thermal history matters. Blanking has no heat-affected zone, but leaves the rollover and burr typical of shearing, which are managed through clearance settings.
4. Both methods have limits on thickness and shape. With laser, the thicker the material, the slower the speed and the worse the taper and tolerance. With blanking, the thicker the material, the more press tonnage is required and the greater the load on the die.
Laser Cutting Tolerance by Thickness
If you choose laser, reflect on the drawing that the achievable tolerance varies with thickness.
| Material | Thickness | Tolerance |
|---|---|---|
| Mild steel | 0.5–3mm | ±0.1mm |
| Mild steel | 3–6mm | ±0.15mm |
| Mild steel | 6–12mm | ±0.25mm |
| Mild steel | 12–25mm | ±0.5mm |
| Stainless steel | 0.5–3mm | ±0.1mm |
| Stainless steel | 3–10mm | ±0.2mm |
| Aluminum | 0.5–3mm | ±0.13mm |
| Aluminum | 6–12mm | ±0.4mm |
These values vary with machine power and conditions. Kerf is roughly 0.15–0.3mm for fiber lasers, and it is safer to assume separate machining after cutting for precision fits.
What to Check in the Design Before Going to Blanking
- Minimum hole diameter — normally keep it at or above the sheet thickness. Holes smaller than the thickness tend to break the punch.
- Hole-to-hole and hole-to-edge distance — too close causes distortion during shearing.
- Specify burr direction — shearing leaves a burr on one side. If it affects assembly interference or safety, state the allowable burr direction on the drawing.
- Die type — single-hit dies and progressive dies differ greatly in die cost and productivity. Give us the expected quantity and we can review which fits.
Practical Decision Sequence
- Is the design finalized? If not, use laser.
- What is the total lifetime quantity? Count all units, not the first order.
- Does the part have many holes and a long contour? If so, the blanking crossover is earlier than you might expect.
- Have you calculated the break-even quantity? Get a die quote and calculate. If total quantity exceeds break-even, choose blanking.
- Have you checked cut edge quality and thickness constraints?
Common Mistakes
- Judging by first order quantity only — if a repeat part is laser cut every time, the cumulative total far exceeds the die cost.
- Ordering a die before the design is finalized — modification cost can approach paying for the die again.
- Leaving hole count out of the cost calculation — laser adds time for every pierce. A part with dozens of holes costs more per part than expected.
- Not specifying burr direction — because of the nature of the sheared surface, a burr always remains on one side. If it is not specified, the problem surfaces at assembly.
See Also
- Laser cutting process details
- Press blanking process details
- Laser or Waterjet? Choosing by Material and Thickness
- Sheet Metal Flat Pattern Calculation: Why Length Changes When Bent (K‑factor)
Send your drawing and expected quantity, and MakeIT can compare both methods and quote them for you.
Have a part to machine?
Upload a drawing to see your quote.



